Predefined Views
You can use predefined views like named views to preselect an orientation, position, and scale for views on a drawing template. You can add the model or assembly reference later using Insert Model in the PropertyManager.
You can save a drawing document with predefined views as a document template.
Inserting a Predefined View into a Drawing
To insert a predefined view into a drawing:
-
In a drawing document, click Predefined View
(Drawing toolbar), or click .
- Click in the graphics area to place the view.
- Set options in the PropertyManager.
- Click
.
You can populate the view as you insert it, or you can populate it later.
Adding Projected Views to Predefined Views
You can add projected views to a predefined view. For example, if you insert a front view, you can project top and right views to create a predefined Standard 3 View. Projected views are automatically oriented and aligned to the original view. The projected views act as predefined views.
You can copy and paste predefined views.
Populating Predefined Views
- Drag. Drag a model from the FeatureManager design tree of an open part or assembly document into the drawing document. All available predefined views are populated.
- Insert Model. Right-click in a predefined view and select Insert Model. Do one of the following:
- In the Insert Model PropertyManager, select a model from the Open documents list, or click Browse and browse to a model file.
- Select a view containing a model.
- In another window, select the model from the graphics area or FeatureManager design tree.
The view and all its related views (such as projected views) are populated when you click
-
Select or Browse. Select a predefined view. In the PropertyManager, under Insert Model, select a name from the Part/Assembly list of models open in the current session, or click Browse and browse to a model file. The view and all its related views (such as projected views) are populated when you click