Welcome to the SOLIDWORKS Web Help

To open the Bill of Materials PropertyManager, do one of the following:

Click Bill of Materials on the Table toolbar, or with a document open, click Insert > Tables > Bill of Materials.
Click the pan icon in the upper-left corner of an existing bill of materials.

BOM Options

Create new table	Creates a new drawing table.
Copy existing table	Copies a BOM saved from a referenced assembly or part. Select a BOM from the list. Select Linked to link the data in the drawing BOM to the assembly BOM. You can unlink the BOMs but you cannot relink them. Changes made in either BOM are reflected in the other. Formatting is not linked.

Table Template

Open table template for Bill of Materials

Choose a standard or custom template. This option is available only during table insertion. The BOM columns match those of the template you select.

The BOM columns match those of the template you select.

Table Position

The stationary corner controls the direction in which the table expands when adding new columns or rows.

The Stationary corner option is not available when you create the table. If the table is anchored on creation, the stationary corner is automatically selected on the drawing sheet in the quadrant nearest the table anchor.

Stationary corner

Top Left	New columns extend to the right and new rows extend below the anchor point.
Top Right	New columns extend to the left and new rows extend below the anchor point.
Bottom Left	New columns extend to the right and new rows extend above the anchor point.
Bottom Right	New columns extend to the left and new rows extend above the anchor point.

Attach to anchor point

Attaches the specified corner to the table anchor.

BOM Type

Top-level only	Lists parts and subassemblies, but not subassembly components.
Parts only	Lists subassembly components as individual items. Does not list subassemblies.
Indented	Lists subassemblies. Indents subassembly components below their subassemblies. Select: No numbering Detailed numbering Flat numbering

If you change the BOM Type of an existing BOM, the document file size increases and may slow performance. You can delete the original BOM, then insert a new BOM with the required BOM Type.
You can dissolve subassemblies in a bill of materials.

Detailed cut list	Displays detailed cut list information when you create a BOM for a document that includes weldment parts.
Dissolve part level rows	Dissolves all weldment part level rows automatically.

BOM Scaling

You can scale the BOM size. Available only after you click the pan icon in the upper left corner of an existing bill of materials in a part or assembly.

Configurations

Lists quantities in the BOM for all selected configurations. Select configurations manually, or click Select all configurations or Unselect all configurations .

Part Configuration Grouping

Specifies how parts with multiple assembly configurations appear in the BOM.

Display as one item number

Uses the same item number for different configurations of a component in different top-level assembly configurations. Each unique component configuration can be present in only one of the assembly configurations in the BOM. This option applies when you create a BOM. If you switch it after the BOM is created, there is no change. When you use this option, set BOM Type to Top-level only.

For example, one configuration of an assembly has the following components:

part1 (config_A)
part1 (config_A)
part1 (config_A)

And another configuration of the same assembly has different configurations of the same component:

part1 (config_B)
part1 (config_B)
part1 (config_B)

A Top-level only BOM that references both assembly configurations with Display as one item number selected appears as:

ITEM NO.	PART NUMBER	config_A / QTY.	config_B / QTY.
1	part1 (config_A)	3	-
1	part1 (config_B)	-	3

To see the configuration name in the PART NUMBER column, go to the part document. In the ConfigurationManager

tab, right-click each configuration, and click Properties. Under Part number displayed when used in a bill of materials, select Configuration Name. Alternatively, right-click a component in the BOM's assembly structure column and click Component Options. Under Part Number, select Configuration Name, then click

.

Display configurations of the same part as separate items

If a component has multiple configurations, each configuration appears in the BOM.

Display all configurations of the same part as one item

If a component has multiple configurations, the component appears in only one row in the BOM.

Display configurations with the same name as one item

If more than one component has the same configuration name, they appear in one row of the BOM. For this option to work properly, Part number displayed when used in a bill of materials in the part must be set to either:

The same User Specified Name
Configuration Name (if different components in the assembly have the same configuration names)

For example, an assembly has the following components:

part1 (config_A)
part1 (config_A)
part2 (config_A)

When you select Display configurations with the same name as one item, the BOM appears as:

ITEM NO.	PART NUMBER	QTY.
1	part1	3

Keep Missing Item/Row

Controls how to handle replaced components in BOM table.

Strikeout	Displays text for the missing item with strikeout formatting.
Replaced components	Keep both with new item number for replacement Keep both with same item number Keep item number and do not keep replaced component Assign new item number and do not keep replaced component Select Replaced components to define how replaced components are handled in the BOM regardless of the Do not change item numbers setting in Item Numbers.

Item Numbers

	Start at	Enter a starting item number.
	Increment
	Follow assembly order	Orders the BOM item numbers the same as the assembly. When selected, you can select Follow sub-assembly order to order the BOM item numbers the same as the subassembly.
	Do not change item numbers	Prevents BOM item numbers from updating when you change item numbers elsewhere.