Allowing Misaligned Concentric Mates

If you have components with two holes, you can mate those components even when the holes are not the same distance apart.

You can align the mate to resolve exactly with either the first or the second concentric mate and apply the offset to the concentric mate that is not aligned. Or you can apply the offset equally to both sets of mated holes. You can also specify an allowed tolerance, beyond which the misaligned mates over define the assembly and display an error.

To allow misaligned mates:

  1. In an assembly, add a concentric mate between the first pair of holes.

  2. Add a concentric mate between the second pair of holes.

  3. In the dialog box, click Create this mate using misalignment options.
    If you do not see Create this mate using misalignment options in the dialog box, go to Tools > Options > System Options > Assemblies and select the Allow creation of misaligned mates option.
  4. In the PropertyManager, select Align Linked mate for the misalignment type.
  5. Click .

    In the graphics area, you can click Section View (Heads-up View toolbar) and zoom to view the edges of each mate. Notice the gap between the surface and edge in the second mate.

    First mate solves exactly
    Second mate displays misalignment distance
In the FeatureManager design tree, the two concentric mates show in a Misaligned folder under the Mates folder.