Physical Product Properties PropertyManager

You can specify configuration properties such as name, description, and BOM options in the ConfigurationManager: CAD Family tab.

This information applies to SOLIDWORKS if you enable the Design with SOLIDWORKS app.

When you create configurations manually, you use the Add Physical Product PropertyManager. When you edit a configuration, you use the Physical Product Properties PropertyManager. Different options are available when you create or edit configurations for parts and assemblies.

To create a configuration in the ConfigurationManager: CAD Family tab , click Inserts new physical product .

To edit a configuration, right-click a physical product and click Edit Physical Product .

Physical Product Properties

Name Specifies the Physical Product name.

Do not use the forward slash (/) or "at" sign (@) in the name. A warning message appears when you close the PropertyManager if the name is blank, contains invalid characters, or already exists.

Description (Optional) Specifies a description that identifies the configuration when you view configuration properties.
Suppress new features and mates (Assemblies only) Suppresses new mates and features in this configuration that are added to other configurations. When cleared, includes the new, resolved mates and features in this configuration.

New features in assemblies include assembly feature cuts and holes, component patterns, reference geometry, and sketches. These features belong to the assembly and not to an assembly component.
Suppress new components (Assemblies only) Suppresses new components in this configuration that are added to other configurations. When cleared, includes the new, resolved components in this configuration.
Suppress new features (Parts only) Suppresses new features in this configuration that are added to other configurations. When cleared, includes the new features in this configuration.

Bill of Materials Options

Set 'Exclude from bill of materials' when inserted into assembly (Assemblies only) Excludes a component, configuration, or model from the bill of materials.

When you select this option, the exclusion occurs the next time you insert the component, configuration, or model.

Child component display when used as a subassembly (Assemblies only) When you use the configuration of the assembly as a subassembly in another assembly, the settings are used with the BOM Type settings in the Bill of Materials PropertyManager. The settings control if and how the child components appear in a BOM of the top-level assembly. Select an option:

Show

Shows the child components in the BOM if dictated by BOM Type in the Bill of Materials PropertyManager. Child components do not show in a Top-level only BOM.

Hide

Hides the child components in the BOM, even if BOM Type shows them. The subassembly appears as a single item in the BOM. For example, a Parts only BOM lists child components as individual items. If you select Hide, the subassembly is listed instead.

Promote

Dissolves the subassembly in the BOM and shows the child components, even if the BOM Type does not show them. For example, a Top-level only BOM lists the subassembly and not the child components. If you select Promote, the Top-level only BOM lists the child components and does not list the subassembly.