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Feature	Example	Topology	Corresponding SOLIDWORKS Feature
Boss	The dimensioned diameters represent boss features.	An external cylindrical face having a complete 360 degrees of arc	No
Chamfer		A planar or conical face or swept line. See DimXpert Chamfer Control Options for maximum width and chamfer width ratios	Yes. Chamfer features defined using Angle distance and Distance distance
Cone		An internal or external conical face	No
Cylinder	The 30, and 50 degree radii represent cylinder features.	A partial or full internal or external cylindrical face External faces with complete 360 degrees of arc may be classified as boss features	No

Feature	Example	Topology	Corresponding SOLIDWORKS Feature
Fillet		A cylindrical face or swept arc: Up to 180 degrees of arc Cylindrical faces are tangent to supporting faces, when present Chained (concatenated) faces have tangency and equal radii	Yes. Constant radius fillet features
Counterbore Hole	A typical counterbore hole (left), and a stepped hole with a blind bottom defined as a counterbore hole (right)	A hole series including two concentric cylinders separated by a plane perpendicular to their axes, with or without a blind end condition of type plane or conic	Yes. Hole Wizard counterbore. If you define a counterbore hole using the Head clearance or Near side countersink options, DimXpert cannot recognize it as a counterbore hole.
Countersink Hole	A typical countersink hole (left), and a chamfered hole defined as a countersink hole (right)	A hole series including a cone followed by a concentric cylinder, with or without a blind end condition of type plane or conic	Yes. Hole Wizard countersink. If you define a countersink hole using the Head clearance or Far side countersink options, DimXpert cannot recognize it as a countersink hole.

Feature

Example

Topology

Corresponding SOLIDWORKS Feature

Fillet

A cylindrical face or swept arc:

Up to 180 degrees of arc
Cylindrical faces are tangent to supporting faces, when present
Chained (concatenated) faces have tangency and equal radii

Yes.

Constant radius fillet features

Counterbore Hole

A typical counterbore hole (left), and a stepped hole with a blind bottom defined as a counterbore hole (right)

A hole series including two concentric cylinders separated by a plane perpendicular to their axes, with or without a blind end condition of type plane or conic

Yes.

Hole Wizard counterbore.

If you define a counterbore hole using the Head clearance or Near side countersink options, DimXpert cannot recognize it as a counterbore hole.

Countersink Hole

A typical countersink hole (left), and a chamfered hole defined as a countersink hole (right)

A hole series including a cone followed by a concentric cylinder, with or without a blind end condition of type plane or conic

Yes.

Hole Wizard countersink.

If you define a countersink hole using the Head clearance or Far side countersink options, DimXpert cannot recognize it as a countersink hole.

Feature	Example	Topology	Corresponding SOLIDWORKS Feature
Simple Hole	(Left) From left to right, a threaded hole with a drill tip bottom, a through hole, and a hole with a flat bottom. (Right) A compound hole comprised of two cylindrical surfaces.	A hole series including a cylindrical face having more than 180 degrees of arc, with or without a blind end condition of type plane or conic	Yes. Hole Wizard and Simple Hole features Holes with near side countersinks are recognized as countersink holes (not linked holes)
Intersect Circle		A circle derived at the intersection of a cone and plane. The cone must be perpendicular to the plane, and it cannot be created from an ellipse. The cone and plane can be interrupted by a fillet or chamfer.	N/A
Intersect Line	An intersect line (blue) forms at the intersection of the part’s bottom plane and the skewed plane (orange). Intersect lines are typically used for dimensioning. In this example, you may need to locate the intersection of the two planes to the left-hand side of the part to control its length.	A line derived at the intersection of two planes	N/A
Intersect Plane	An intersect plane is derived at the intersection of the larger cylinder and conical face. Intersect planes are typically used to locate the starting or ending location of a tapered surface.	A plane derived at the intersection of a concentric cylindrical and conical face.	N/A

Feature	Example	Topology	Corresponding SOLIDWORKS Feature
Intersect Point	An intersect point, shown as an origin, is derived at the intersection of a plane (blue) and a cylinder (orange). Intersect points are typically used to locate the referencing hole/cylinder. In this example, you may need to locate the hole's pierce point to the right-hand side of the part (creating a horizontal dimension).	A point derived at the intersection of a plane and the axis of a cylindrical or conical face.	N/A
Notch		Two parallel planes bounded by a plane perpendicular or a cylinder tangent to the side planes, with or without a planar blind end condition	No
Plane	Each planar face (gray) represents a single plane feature. You can combine the blue or orange faces to define a compound plane.	A planar face	N/A

Feature	Example	Topology	Corresponding SOLIDWORKS Feature
Pocket	An example of a through pocket (orange) embedded in a blind pocket (blue)	An internal extruded type closed profile, with or without a planar blind end condition	No
Slot	A blind square slot (left) and a through slot with radial ends (right)	Two parallel planes bounded by two planes perpendicular or two cylinders tangent to the side planes, with or without a planar blind end condition	No
Surface		A non-prismatic face	No

Feature	Example	Topology	Corresponding SOLIDWORKS Feature
Width	The pairs of planes that comprise each dimension represent a width feature	Two parallel planes with opposing normal vectors	No
Wedge		Two nonparallel planes with opposing vectors	Yes Create Width/Wedge Feature in the feature selector
Sphere		An internal or external spherical face	No

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