Broken-out Section

A broken-out section view cuts away a portion of an assembly in a drawing view to expose the inside. Cross hatching is automatically generated on the sectioned faces of all components.

A broken-out section is part of an existing drawing view, not a separate view. A closed profile, usually a spline, defines the broken-out section. Material is removed to a specified depth to expose inner details. Specify the depth by setting a number or by selecting geometry in a drawing view.

If you create a broken-out section of an exploded view, you cannot collapse the exploded view.

This example shows (1) wall thickness and shaft and (2) how the shaft is welded to the cap:
drw_broken_out_ex.gif
Broken-out section of a pictorial (isometric, trimetric, dimetric) view. The depth is normal to the sheet:
brokenout_ex.gif

Creating a Broken-Out Section

To create a broken-out section:

  1. Click Broken-out Section tool_Broken_Out_Section_Drawing.gif (Drawing toolbar), or click Insert > Drawing View > Broken-out Section.
    The pointer changes to pointer_add_curves_freeform.gif.
    If you want a profile other than a spline, create and select a closed profile before clicking the Broken-out Section tool.
  2. Sketch a profile.
  3. Set options in the Section View dialog box. If you do not want to exclude components or fasteners from the broken-out section view, click OK.
  4. Set options in the Broken-out Section PropertyManager.
    Use 3D drawing view mode to select an obscured edge for the depth of a broken-out section view.
  5. Click PM_OK.gif.

Editing or Deleting a Broken-Out Section

To edit or delete a broken-out section:

Right-click the broken-out section in the FeatureManager design tree and select one of the following:
Option Description
Edit Definition Set options in the Broken-out Section PropertyManager, then click PM_OK.gif.
Edit Sketch Select the sketch entity and edit it, then close the sketch.
Delete  

Broken-Out Section View on Alternate Position View

You can add broken-out section views to alternate position views.

Alternate position view Broken out section view on alternate position view

To add a broken-out section view to an alternate position view:

  1. In an alternate position view, click Insert > Drawing View > Broken-out Section .
    Broken-out sections can only cut the reference configuration of the drawing view, not the alternate positions.
  2. Sketch a closed profile such as a spline.
  3. In the PropertyManager, set options.
  4. Click .

Broken-Out Section View on Detail View

You can add broken-out section views to detail views.

To add a broken-out section view to a detail view:

  1. In a detail view, click Insert > Drawing View > Broken-out Section.
  2. Sketch a closed profile such as a spline.
  3. In the PropertyManager, set options.
  4. Click .

Broken-Out Section View on Section View

You can add broken-out section views to section views.

Broken out section view on section view Enlarged image of broken-out section view

To add a broken-out section view to a section view:

  1. In a section view, click Insert > Drawing View > Broken-out Section.
  2. Sketch a closed profile such as a spline.
  3. In the PropertyManager, set options.
  4. Click .