Interactive Feature Recognition Selections
Standard Feature Types
| Feature type | Selected entities | Required selection | Example |
|---|---|---|---|
| Boss Extrude or Cut Extrude | Face | Select a model face representing the sketch for the feature.
For all extrudes, FeatureWorks recognizes the Blind end condition. For cut-extrudes, FeatureWorks also recognizes Through All and Up to Next. |
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| Boss Extrude or Cut Extrude | Edges or Loop | Select the complete set of edges, or the loop, representing the sketch for the feature. | |
| Boss Extrude or Cut Extrude | Parallel faces | Select a planar face that defines an extrude and select Check parallel faces. | |
| Boss Extrude or Cut Extrude | Non-Planar faces | Select the non-planar face of the boss extrude, then select the non-planar supporting face in the Up to face box. The boss extrude must be an exact offset from the supporting face. | |
| Boss Extrude or Cut Extrude | Non-Planar faces | Select the non-planar face of the cut extrude, then select the non-planar supporting face in the Up to face box. The cut extrude must be an exact offset from the supporting face. | |
| Boss Revolve or Cut Revolve | Face | Select the complete set of faces representing the sketch for the revolve feature.
If the Chain revolved faces check box is selected, select a single face for this revolve. The FeatureWorks software selects the chained faces. |
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| Cut Revolve | Face | Select the face of the cut revolved feature, and verify that Chain revolved faces is cleared. | |
| Chamfer | Face | Select a model face representing the chamfered face. | |
| Draft | Face | Select the drafted faces and a face representing the neutral plane. | |
| Fillet/Round | Face | Select a model face representing the filleted face. | |
| Fillet/Round | Face | Select a variable radius fillet. | |
| Hole | Face | Select the complete set of faces representing the sketch for the hole feature. FeatureWorks recognizes Hole Wizard holes.
FeatureWorks recognizes these end conditions: Blind, Through All, and Up to Next. FeatureWorks also recognizes these end conditions when you use the resize tool. |
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| Base-Loft | Face | Select an End Face 1 and End Face 2. | |
| Rib | Face | Select a face unique to the rib. | |
| Rib | Face | Recognize ribs that are extruded using Normal to Sketch as the Extrusion direction.
Select the face (on the rib) that was used to create the normal to sketch rib. |
|
| Rib | Face | Recognize ribs that include a negative draft.
Select a face unique to the rib. |
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| Shell | Face | Select the face at the end of the shell feature. Only shell features with uniform thickness can be recognized. Only shell features created with an inward shell can be recognized. | |
| Boss Sweep or Cut Sweep | Face | Select the face at one end of th sweep under End Face 1, and select the face at the other end under Select Face 2 | |
| Boss Sweep or Cut Sweep | Face | Select the face on the upper boss for End Face 1 and select the supporting face of the boss for End Face 2/Support Face. | |
| Boss Sweep or Cut Sweep | Face | Select the face with the opening as End Face 1 and select the other end of the sweep as End Face 2. | |
| Boss Sweep or Cut Sweep | Face | Select the face at one end of the sweep as End Face 1 and select the face at the other end of the sweep as End Face 2. | |
| Boss Sweep or Cut Sweep | Face | Under Cut faces, select the faces of the sweep. |
Sheet Metal Feature Types
| Feature type | Selected entities | Required selection | Example |
|---|---|---|---|
| Base Flange | Face | Select any one of the base flange faces. | |
| Sketched Bend | Fixed face | Select the fixed face along which the part was bent. Sharp bends cannot be recognized. | |
| Hem | Face | Select the hem face or the bend face. | |
| Edge Flange | Face | Select any one of the edge flange faces. | |
| Miter Flange | Face | Select the inner or outer flange face of the miter flange that meets the fixed face. You can recognize miter flanges with offset or on multiple edges. Miter flange recognition has limitations. |